Provided by: pcb2gcode_1.1.4-git20120902-1.1build5_amd64 
NAME
pcb2gcode - command-line tool for engraving PCBs using CNCs
SYNOPSIS
pcb2gcode [options]
DESCRIPTION
This manual page documents briefly the pcb2gcode command.
pcb2gcode is a program that takes the files typically produced by PCB (printed circuit
board) designing tools, in particular Gerber (RS-274X) and Excellon (an RS-274C variant)
files as parsed by gerbv, and produces files that can be used to control a CNC (computer
numerical control) milling machine. These files are in G code format (RS-274D/NGC) that
can be read, for example, by the linuxcnc EMC2 system.
When these files are executed, an engraving bit is used to remove the surface from a
copper covered circuit board, thus creating isolated areas. In another step, holes are
drilled into the board at the appropriate positions, and it can be cut out in another
step. (For each step, a separate output file is created.)
OPTIONS
These programs follow the usual GNU command line syntax, with long options starting with
two dashes (`-'). A summary of options is included below.
Instead of passing all options on the command line, nearly all options can be stored in a
file named millproject. There, options are given one per line as option=value pairs
(without the two dashes), and can be separated by blank lines and commented (everything
after a `#` character is treated as a comment). Options that don't take an argument (like
--metric) are entered as option=1 there.
Unless configured otherwise, numeric values are in units of inch and inch/minute. When the
--metric option is given, they are in mm and mm/minute.
--front filename.gbr
Engrave the front side according to the given file (typically used in two-sided
boards).
--back filename.gbr
Engrave the back side according to the given file.
--outline filename.gbr
Cut out the board to the shape exposed in the given file. Typically, there is only
a polygon in this gerber file. Alternatively, this file can contain a closed line
chain (see --fill-outline).
--drill filename.cnc
Convert the given file (containing drill sizes and positions) to G-code.
For every option --x that takes a filename, there is an --x-output option that specifies
where the resulting G-code is saved, defaulting to x.gbr. Instead of giving each output
file name, the --basename option can be used; the base name will be used as a prefix to
the default output file names.
The parameters that define engraving are:
--zwork unit
Z-coordinate at which engraving happens
--zsafe unit
Z-coordinate for movements between engraving steps
--mill-feed unit/minute
feed rate at which engraving takes place (horizontal speed)
--mill-speed rpm
spindle speed during engraving (rounds per minute)
--offset unit
distance by which the tool movement will be outset from the contours in the gerber
file to be engraved
If this distance can't be satisfied because copper areas are too close, a warning
will be printed and the line will be drawn between the areas. This behavior can be
used to get voronoi-style (flood-filling) areas; simply set the offset to a large
value (like 1 inch).
--extra-passes number
number of additional isolation passes
For each extra pass, engraving is repeated with the offset width increased by half
its original value, creating wider isolation areas.
The parameters that define outline cutting are:
--cutter-diameter unit
amount by half of which the tool path is outset from the shape in the outline file
--zcut unit
Z-coordinate indicating where the outline cutting ends
--cut-feed unit/minute
feed rate at which outline cutting takes place (horizontal speed)
--cut-speed rpm
spindle speed during outline cutting (rounds per minute)
--cut-infeed unit
maximum Z distance that is cut away in a single pass (positive value; if less then
zcut's value, there will be more than one pass)
--fill-outline
If --fill-outline is given, it is assumed that the outline file contains not a
polygon but a closed chain of lines. The board will be cut along the centres of
these lines.
--outline-width unit
thickness of the lines that form the outline (if --fill-outline is given)
Drilling takes another set of options:
--zdrill unit
Z value down to which will be drilled
--zchange unit
Z-coordinate for movements with the drill head
--drill-feed unit/minute
feed rate for drilling (vertical speed)
--drill-speed rpm
spindle speed during drilling (rounds per minute)
--milldrill
If --milldrill is given, the milling head will be used to drill the holes in the
PCB. Holes up to the size of the milling head will be drilled regularly (possibly
creating a bigger hole than intended), the other holes are created by moving the
head in circles using the feed and infeed parameters used in cutting.
--drill-front
use the coordinates of the front side for drilling instead of the coordinates of
the back side
These options govern the general behavior of pcb2gcode:
--dpi dpi
resolution used internally (defaults to 1000)
--mirror-absolute
mirror operations on the back side along the Y axis instead of the board center,
which is the default
--svg filename
export the resulting contours to an SVG (scalable vector graphics) file
The only options that can't be used in the millproject file are the common ones:
-?, --help
Show summary of options.
-v, --version
Show version of program.
SEE ALSO
gerbv(1), pcb(1).
For further information about pcb2gcode, see the project wiki ⟨http://sourceforge.net/
apps/mediawiki/pcb2gcode/⟩.
AUTHOR
pcb2gcode was written by Patrick Birnzain, loosely based on an earlier program of the same
name by Jeff Prothero (Cynbe ru Taren), which in term was based even more loosely on
Matthew Sager's gerber_to_gcode.
This manual page was written by chrysn <chrysn@fsfe.org> for the Debian project (and may
be used by others).
2010-11-10 PCB2GCODE(1)